Rear Actuator Cap

Part Studio 2 — Rear Actuator Cap1. Revolved Outer Shell & PocketCreate a new tab: PS2 Rear Actuator Cap.Sketch on the Front Plane (Shift + S, press N).Draw a vertical construction centerline on the Origin.Draw the closed half-profile:Start at Origin: draw a horizontal line right by 18 mm (sets $36\text{ mm}$ outer diameter).Draw a vertical line up by 25 mm (total cap length).Draw a horizontal line left toward the centerline by 3 mm (sets the $3\text{ mm}$ end wall thickness).Draw a vertical line down by 22 mm (leaving the inner cavity).Draw a horizontal line left back to the vertical center axis.Close the profile along the centerline to the Origin.Click Revolve (Shift + W), select the profile, choose the vertical centerline as the Revolve axis, and confirm with the Green Checkmark.2. External M32×1.5 ThreadOn the open cylindrical mating neck of this cap (the stepped section that threads into the Main Body):Apply the Thread tool:Select the outer cylindrical surface over a depth of 10 mm from the front edge.Set to M32×1.5 External.3. Motor CavitySelect the rear exterior flat face of the cap and create a sketch (Shift + S).Press C for Circle, snap to the center origin, and dimension to 22 mm.Extrude (Shift + E) $\rightarrow$ Remove $\rightarrow$ Blind to a depth of 18 mm.4. Center Plunger Clearance BoreSketch on the bottom floor of the 22 mm motor pocket.Draw a circle snapped to the center origin: dimension to 8.2 mm.Extrude (Shift + E) $\rightarrow$ Remove $\rightarrow$ Set End type to Through all to clear through the entire remaining wall along the central axis.5. Cable Exit HoleCreate a reference plane tangent to the cylindrical outer face, or use the Right Plane.Create a sketch: place a circle of diameter 4 mm.Dimension the center of this circle to be 10 mm from the rear flat face.Extrude (Shift + E) $\rightarrow$ Remove $\rightarrow$ Up to next (or Blind through the outer wall) into the internal motor cavity.6. E-Stop Side Mounting Through-HoleOn a plane oriented $90^\circ$ to the cable exit hole (e.g., Front Plane):Sketch a circle of diameter 16 mm.Dimension its center to align with the E-stop button location.Extrude (Shift + E) $\rightarrow$ Remove through the side wall.Select the Counterbore or sketch an outer circle of diameter 20 mm on the exterior face:Extrude $\rightarrow$ Remove to a depth of 3 mm to create the recessed seat for the button flange.

Parameters

Every value above is a live dimension. Open a model like this in the editor and each one becomes a slider you can drag before exporting.